<!DOCTYPE html
  PUBLIC "-//W3C//DTD HTML 4.01 Transitional//EN">

<!--
Copyright (c) 2006 UGS Corp.

All Rights Reserved.

This software and related documentation are proprietary to UGS Corp.
-->
<html>
   <head>
      <meta http-equiv="Content-Type" content="text/html; charset=UTF-8">
      <title>Controlling the Analysis Output</title>
      <script language="javaScript">
        abridged="false";
        displayConditions=new Array();
      </script>
      <link type="text/css" href="../css/main_styles.css" rel="stylesheet">
   </head>
   <body class="bodydocs" onload="top.pageLoader()" bgcolor="#FFFFFF">
      <div class="title_topic2" id="xps10_pagetitle">Controlling the Analysis Output</div>
      <hr noshade="true"><a name="gsprelim_10823"></a><p class="para_topic">The types of analysis quantities to be printed are specified in the Case Control Section.  This problem requires displacements and element stresses, so the following commands are needed:      </p>
      <table width="100%" align="center">
         <colgroup span="1">
            <col span="1" width="38*">
            <col span="1" width="160*">
         </colgroup>
         <tr>
            <td colspan="1" rowspan="1"><a name="gsprelim_10826"></a><pre class="indent"> DISP=ALL </pre></td>
            <td colspan="1" rowspan="1"><a name="gsprelim_10828"></a><p class="para_td">(prints all GRID point displacements)</p>
            </td>
         </tr>
         <tr>
            <td colspan="1" rowspan="1"><a name="gsprelim_10830"></a><pre class="indent"> STRESS=ALL </pre></td>
            <td colspan="1" rowspan="1"><a name="gsprelim_10832"></a><p class="para_td">(prints all element stresses)</p>
            </td>
         </tr>
      </table><br><a name="gsprelim_10833"></a><p class="para_topic">In order to help verify the model results, we will also ask for the following output quantities:      </p>
      <table width="100%" align="center">
         <colgroup span="1">
            <col span="1" width="37*">
            <col span="1" width="162*">
         </colgroup>
         <tr>
            <td colspan="1" rowspan="1"><a name="gsprelim_10836"></a><pre class="indent"> FORCE=ALL </pre></td>
            <td colspan="1" rowspan="1"><a name="gsprelim_10838"></a><p class="para_td">(prints all element forces)</p>
            </td>
         </tr>
         <tr>
            <td colspan="1" rowspan="1"><a name="gsprelim_10840"></a><pre class="indent"> SPCF=ALL </pre></td>
            <td colspan="1" rowspan="1"><a name="gsprelim_10842"></a><p class="para_td">(prints all forces of single point constraint; i.e., reaction forces)</p>
            </td>
         </tr>
      </table><br><a name="gsprelim_10843"></a><p class="para_topic">The following command will yield both unsorted and sorted input file listings:</p><a name="gsprelim_10844"></a><pre class="indent">
    ECHO=BOTH
  </pre><a name="gsprelim_10845"></a><p class="para_topic">TITLE and SUBTITLE headings will appear on each page of the output, and are chosen as follows:</p><a name="gsprelim_10846"></a><pre class="indent">
    TITLE=HINGED BEAM
  
    SUBTITLE=WITH CONCENTRATED FORCE
</pre><a name="gsprelim_10848"></a><p class="para_topic">Finally, we select constraint and load sets as follows:</p><a name="gsprelim_10849"></a><pre class="indent">
    SPC=100
  
    LOAD=10
</pre><a name="gsprelim_10851"></a><p class="para_topic">The complete Case Control Section is shown below.  The commands can be entered in any order after the CEND delimiter.</p><a name="gsprelim_10852"></a><pre class="indent">
CEND 
ECHO=BOTH 
DISP=ALL 
STRESS=ALL 
FORCE=ALL 
SPCF=ALL 
SPC=100 
LOAD=10 
TITLE=HINGED 
BEAM SUBTITLE=WITH 
CONCENTRATED FORCE
  </pre></body>
</html>